- [Instructor] One of the more unique representations we use
inside of a SOLIDWORKS drawing is a model break view
within a drawing.
Now unlike other views that we create in SOLIDWORKS drawings
this view actually starts in the SOLIDWORKS part
or SOLIDWORKS assembly,
and that's where we actually create the view
or the settings for the view
and then we can display them inside of a drawing view
in SOLIDWORKS, so let me show you what I mean.
Right here, we have a part file.
It represents a box with a pipe running to another box.
This is a pretty long item.
When I switch over to the drawing template
that I want to put it on, it's just too big
and it's isometric and I want to shrink it down
so that I can see it a little bit more clearly and really,
all I want to do is cut it from here to here
and bring it together.
So I'm going to switch back to my part file.
We're going to go up to insert,
go down about half way and we see model break view.
I'm going to click on that
and automatically, it brings up this green and red plane
and we're setting the distance for the break.
Now you can see here, we have model break steps,
so you can do multiple steps in this break,
so we're just going to do a single break right now.
We're going to keep it aligned to the front plane.
You can switch it to the other planes, as well.
You can change the angle, if you want,
but I'm just going to leave it straight on.
You can also set the gap distance in between the result
that you get after you make this break.
So I'm going to drag this green plane over a little bit more
and make my break a little bit bigger.
I'm going to do the same thing with the red plane.
I'm just left mouse button clicking down
and dragging the arrow.
If we go to the next tab, we have the style.
So if I zoom in right now,
we're just using a straight break.
We can also use the zigzag break, a single zigzag break
and a pipe break, saddle shape.
I'm going to leave that one
and I'm also going to shrink down the gap in between these,
so I'm going to set this to five inches.
Maybe a little bit bigger, let's go to seven.
All right, you can also mess with the shape intensity,
just really doesn't matter,
but in case you do want to do it,
you can change this slider from one direction to the other
and it will embellish or under embellish any of the features
that you see there.
Go ahead and click okay,
and now we've got a model break view,
and you see this
is shown underneath the default configuration.
I can right click and hit hide model break view
and it goes back to the original view.
If you're in the model break view,
I'm going to say show model break view,
you won't be able to edit your sketches
and edit your features.
So you'll want to go back to the configuration
and say hide model break view,
go back to your feature tree,
and now you can right click and start editing sketches
and editing other features.
Once we have this, I'm going to go ahead and click save
and now I'm going to switch over to my drawing.
Switching over to my drawing,
I'm going to click on the drawing view.
Now if you go over here basically
to show the model break view,
you just want to choose a different configuration.
So we have the option here,
show in exploded or model break state.
I'm going to click on that
and now you see here, model break view one.
Now if I had multiple breaks,
I could select between them,
but this is the only one,
so it automatically goes to that.
I can move my model a little more
in the center of the screen and click okay,
and now we've inserted a model break view within a drawing.
Pretty easy.