- One other nice feature that we have inside
of SolidWorks Drawing views
is the use of an Alternate view.
Now, an Alternate view gives us the possibility
of showing a different positional
configuration of an assembly.
In this specific example we have a wrench
that you can squeeze down the handle onto,
which enacts the motion of the wrench or the clamp.
We can show an alternate view of this
using our alternate position drawing view.
How do we do this?
We're going to go up to the insert dropdown,
go to drawing view
down to alternate position.
Click on that.
We're now going to select the view
to create the alternate position.
This alternate position is actually going to
show up inside of a current view.
So, I'm going to select this view.
We see the Property Manager updates here on the left
and we're going to keep it on New Configuration
and click okay.
Now this is going to switch us over
to our SolidWorks Assembly view
and automatically open up the Move Component dialog box.
And what this is asking you to do is
drag your assembly
into this alternate position that we're creating.
So I'm going to go out here and left mouse button
click down on the handle
and drag it down.
And you can see that the assembly is moving accordingly.
Our bolt in the back is moving out based on the
clamp pieces that have adjusted over here.
So now that I'm done and I've got the position that I want
I'm going to go over to the left side,
click on the, Okay, the green check box.
It's going to bring me back into my SolidWorks drawing.
And now you can see in the dashed outline
we have the alternate position of this assembly.
We've created an alternate position view.
And if you go over to the feature tree
on the left and expand to this first drawing view
you can see that alternate position here as well.
Pretty handy and pretty easy to do.
If you forget where that command is, you can go up here
to the search dropdown, just change it to Commands
and start typing in alternate position and it'll come up.
And as always, you can use the show command location
to find that.
We have a bunch of views that we don't use all the time.
This is one of them.
Be sure to know how to locate it either here
on the drawing tab or using the search tool up above.