- To get started with our assembly let's start
by creating a new assembly file
using assembly template.
In the property manager cancel the begin assemblies
properties dialogue, and let's first save our assembly,
place it in the assembly components folder,
and let's name it top level assembly.
Now from the command manager assembly tab
select the insert components command.
Select the browse button and from the assembly
components folder control select the flywheel
and cone rod models.
So we can insert these components simultaneously
into our assembly environment.
In the open documents box select only the flywheel
so we place it as the first component.
Make sure to select the pushpin to keep
this dialogue open.
Click the green okay icon so the flywheel's origin
is automatically fixed to the assembly's origin.
Remember it is a best practice to have your
first component fixed or fully defined.
Now select the cone rod part from the open
documents box and click anywhere in the graphics
view to place it and okay to complete the command.
Notice that the flywheel part in the feature manager
is prefixed with the letter F, which indicates
the component is currently fixed.
Let's right-click on this component and select
the float option so it is no longer fixed
and that we can constrain it with mates instead.
From the assembly tab select the mate command
and follow my lead as we get
these components constrained.
Make the front plane of the flywheel coincident
to the front plane of the assembly.
Make the horizontal flywheel face 15 degrees
from the top plane of the assembly, and if necessary
flip the dimensions so the model is represented
the same as mine in the graphics view.
Make the flywheel's origin coincident
to the origin of the assembly.
Note at this stage that even though we do not
have the fixed symbol prefixing the component name
that it is actually fixed since the component
is currently fully defined.
This is evident by the lack of the minus symbol
prefixing the part name.
Now let's keep going.
Make the cone rod inner cup face concentric
to the flywheel shaft.
Add a distance mate of three millimeters
to these two faces.
Now click okay to close the mate properties.
Select the cone rod in the graphics view
and from the configuration drop down
just above the context toolbar
select the cone rod cup configuration as
the reference configuration and select
the green tick mark to accept the selection.
Select cone rod final in the feature manager.
From the insert components flyout menu
select the copy with mates command.
Under the mates section select repeat for both,
and then okay to complete the command.
Select the new instance of the cone rod
and change the configuration to cone rod.
We now have a complete cone rod assembly.
In the graphics view rotate the cone rod cup instance
so we can mate the two sections together.
Control select these two faces and let's make
them coincident using the context toolbar options.
In the graphics view control and select the flywheel
and at the same time drag to the left or right
to create another instance in the graphics view.
Now let's activate the mate command and follow
along as I get the second instance into position.
Now we will need a concentric mate
between these shafts and flip the alignment.
Now make these two faces coincident
and these two faces parallel to align
the two components with each other.
Now change the second flywheel configuration
to spline shaft and again confirm your change.
Now that you've seen how we've gone about this,
on your own add another cone rod instance
and in the same way as before mate it
to the second flywheel instance.
When you're done I will see you in the next video.