Next, we are going to use the previous sprocket
and a configuration to create the large sprocket
for our chain assembly.
Now, we'll be getting to assemblies
in chapter three of our project.
For now, do a Save As Copy and open
and name the file Sprocket Final Configs.
And go ahead and save that.
Let's start by adding a new configuration.
Select the Configuration Manager.
We will right-click on the part name
and select the Add Configuration command.
Let's name it Large Sprocket
and then we'll say OK to that.
This configuration is now automatically activated for us
and to easily access the features,
we will split our Feature Manager.
Now, click on the Cut Extrude1 feature,
so we can see the dimensions in the Graphics view
and let's change the dimension to thirteen millimeters.
Sketch a circle on the front face of Boss Extrude3,
which we will use for a boss extrusion.
And let's offset it five millimeters
from Cut Extrude1's edge.
Also, let's then do a Convert Entities on the same inch
and let's go ahead and extrude this twenty-four millimeters.
We'll go with a Blind End Condition
and make sure that we're extruding to the front.
Let's edit Boss Extrude3
so we can make some changes that are only relevant
to this configuration.
Change the End Condition to Blind
and set the distance to seven millimeters.
Now, go ahead and activate Direction2
and do a Blind Extrude to twenty millimeters.
To the bottom of the Properties Manager,
we have Configuration Options.
Select the This Configuration option
and now we can go ahead and complete the command.
Sketch a circle on the front face of Boss Extrude1
and roughly vertical to the origin.
We will cut away some of the material
to make the sprocket lighter.
Let's constrain the center of the circle
vertically to the origin
and let's also add a twenty-five millimeter diameter.
Add a forty-five millimeter dimension
between the origin and the center of the circle
and let's go ahead and do an extruded cut
and we will use a Through All End Condition.
Let's pattern this hole.
Under the Linear Pattern flyout,
select the Circular Pattern command.
Use a temporary axis for the pattern axis.
Let's select equal spacing
and set the number of instances to six.
Okay, you complete the command
and let's go ahead and turn off the Temporary Axis again.
That's it.
Go ahead and add fillets and chamfers as before
and when you are done, save your work.
In this same manner, I will create additional gears
and sprockets, which we will use
during the assembly of our design.
I'll see you in the next video
where we'll be modeling the final part
before assembling our project.