- [Instructor] Here I have
my main body for the valve housing.
At this point, I wanna go in and realign
the sleave that's gonna go through the main body.
You can see when we initially created it
it is over at the absolute of the part,
and not at the center of the part.
I'm just gonna double click on the sketch,
and I'm gonna come to the center point here.
Just gonna hover for a moment, highlight,
pick the coincident, and delete it.
Now that it's deleted, I can move it off to the side.
I can double click on the auto constraint that's there.
That's gonna be 57.2 divided by two.
Close that.
I wanna take the center point
to my horizontal axis.
The last thing I wanna do
is change the size of this diameter.
I'm gonna double click on that diameter,
and that's gonna be 50.8.
Finish out,
and just like that, the sketch has moved,
but it's buried inside of the solid.
You can't see it.
If I highlight it, just single click in this part navigator,
sketch number two, you can see that it is there.
Could do my extrude.
Gonna come up to the 40.5.
I do want this set to unite.
I'm not doing anything extra to this.
I'm simply just making a solid for that sleeve
and uniting it.
Select OK.
Now, here I want to go in and put in my holes.
Click on the hole function.
For the first hole, we'll come in here.
They're gonna go to the center, right there, of that edge.
Pick that, Arc Center.
You'll notice that it is running through.
Set the through body.
I have my diameter.
Subtract.
Perfect, select OK.
Next, I wanna come in and put in my hole function again.
This time, I'm gonna pick the sleeve face at the top,
right at the center point, Arc Center.
What you're gonna notice is I'm gonna get this
unable to create the body.
Basically the hole's much too large going in this direction,
and it's basically, you're just wiping out the entire solid.
This is one of those
where I need to work through that alert.
If I come in here and just simply make this
a little bit smaller, for example, you'll see there it is.
It's no longer completely destroying the entire solid.
For this hole, I should say,
I need to make it a counter bore.
So, I'm gonna change the form from simple.
Select Counterbored.
What's my c-bore diameter?
25.4.
My c-bore depth is 6.35.
There's my diameter.
There's my depth.
What's my diameter on the hole?
14.3, and the depth.
You can see it's punching through the entire part.
I don't want that.
I'm just gonna change that.
Save value.
Put in my depth value.
It's gonna tip angle of 118 degrees.
You can see, it doesn't cut all the way through the part.
And select OK.
Next, I'm going to put in one more hole.
This hole is gonna be a simple hole.
You can see, I can fill in these values now,
so I don't necessarily get the little error message
that wants to pop up sometimes.
For the diameter of that hole,
I'm just gonna say five milometers.
Pick my face.
Make sure you're getting the face here.
Once you pick you face, it's gonna put you into the sketch.
This allows you to position the center point.
I wanna specify my vector,
pick my, in this case, Z
off of my axis,
select OK, and there's my point.
I'm just gonna close out Sketch Point,
because I only want to create one of these.
For this, I wanna take it and position this point.
I wanna take you, get that point.
I wanna go to my horizontal axis,
and just say, point on curve.
Next, dimension.
I want to dimension this point
to my center point.
I pick my center point.
The type of dimension that I'm using here,
and you have to be very specific,
you have to use horizontal.
You wanna make sure you change this to horizontal.
Now I can enter in that value,
and let's take a look here.
That's gonna be.
Now that I have my value entered in
I'm just gonna simply close this and go to Finish.
It's five milometers.
Now you'll notice that I have it set
so it's going to depth 50.
Gonna leave everything as is, and I'm gonna say subtract.
Select OK.
The last thing I need to do for this hole is make a pattern.
Once again, I'm gonna come in,
go up to Pattern Feature this time,
but not the pattern geometry.
Again, they work very similar,
but I just want to pattern the hole.
What feature do I wanna pattern?
That.
What's my vector?
Now, you'll notice that if I come in here,
and use this cylindrical face,
it automatically gives me my center point,
gives me my vector, axis rotation.
I want three of these.
And, select OK.
So, there's my holes
cutting all the way through the part.
That is your completed valve housing.