- [Instructor] Now that I have all my sketches for my
valve housing, I'm gonna go ahead and create my solids,
the main bodies so here I have my sketch for my main body.
I'm just gonna go in, do an extrude, specify my sketch.
So you can go and either enter in the value if you want
or you can do simple addition, subtraction,
that type of thing here inside of these text fields.
Basically, the systems like this
are super advanced calculators
so there's something that you wanna put in here,
as far as a formula goes, you can do it.
So in this case, my distance is 57.2 for the entire length
of the body but I only want half of that.
So I'm just gonna say divide by two, hit enter,
and there is my initial extrude.
Boolean is set to none because there's no other bodies
in the file so by default it has to be none
and select your point.
Now that I have my main body, I'm going to go in,
gonna hide that sketch and I'm gonna show, sketch 001.
So here I'm gonna create the flanch.
I'm gonna start out with one, and then I'm gonna
make a pattern from that one.
So the first thing I need to do is
make my extrude, make my sketch.
Now you'll see it picked the entire sketch.
In this case, I wanna makes sure
that I have my selection intent set correctly.
I'm using connect the curves.
I wanna pick all of the curves that are connected here.
What's my depth, 10 millimeters.
I wanna make sure my Boolean in this case is set to none.
Again, I don't want this unite two main solids.
I want this to be a separate solid
because I'm gonna perform additional functions
before I do the patent.
Select the K, I want to put in a hole.
I'm gonna use a general vole.
The hole I want to place is going to be
at the center of this edge
so I wanna make sure I highlight the center,
I wanna make sure that circle or arc center
is also turned on for my selection intent,
just use single point, so I come down here,
highlight that edge, and make sure I get that point
very carefully, I have that point.
Once I select that point, arc center,
I put in my value, 12.7, I wanna go through lobby
and I want subtract turned on in this case
cause I want this to be a hole,
I want to remove from that body.
Select okay, put in my edge blend,
so I'm gonna break the edge here,
two millimeters is just fine.
And select okay.
Now that I have that body completed,
I want to make a pattern of this body.
Now I don't wanna use pattern feature
cause I'm actually going to have pattern geometry.
I'm taking the whole body of the whole, the edge blend,
the extrude, everything is one body.
And do the pattern.
So I'm going, select pattern geometry,
what do I want pattern, I wanna pattern this,
what's my vector, just pick the Z axis.
I'm gonna use Count and Span, I have a total of three,
going around around my 360 degrees.
Select okay, now I'll go back and do my unite.
I wanna unite this as my target,
this is my tool, and tool, and tool.
Now notice, if I hit okay right now
I have target turned on,
I wanna make sure that's turned off.
I want these to be a separate, unite all to itself.
I don't want the actual feature copied out
and have an additional feature.
So I want this all as one body.
I don't want that additional feature
so I'm gonna turn that off, select okay.
Next, I'm going to do my edge blend.
I'm going to blend these corners.
Again, I picked one, you'll notice
I get the racetrack effect that's hitting all
of the tangent curves cause of my selection intent.
Two millimeters, select okay.
Now that I have that, I'm going to go in and go to more,
go to mirror geometry.
Again, I'm taking the entire body, not a separate feature,
so I'm just gonna say mirror geometry.
I wanna take that body across face
of the plane in this case.
I'm gonna use this face, select okay, and then unite.
And there I have my main body with my flanges,
filled out, and holes put in.