- [Narrator] There's a tool that you should become
intimately familiar with within the sketcher,
and it's the sketch analysis.
V5 is very picky about your sketches.
You need to have certain parameters set
within each sketch in order for them to be useful to you
outside of the sketch.
Now, if I go under the Tools, Sketch Analysis,
you'll see I have an icon as well for it
down at the bottom.
And what I want you to notice is that it's giving me
a list of all the geometry
that I currently have in the sketch.
You'll see I have an open profile.
I have an isolated line, isolated line.
I have a point.
So what's happening is it's giving me a warning.
You can see the warning for isolated point.
V5 does not like to use points making a solid.
You can't extrude out a point
or pad out a point to make a solid.
So it's saying, "Hey, you got a problem with this."
And that's what's nice about the sketch analysis
is that you don't really have to go looking
because the sketch analysis tool will do
the looking for you.
And it'll tell you that you do have
some potential issues with the sketch.
So, I can select that point here.
I can right mouse click and say reframe on it.
Maybe you're dealing with a very large part,
and you need to see where that point's at.
You can pick that point and zoom out on it a little bit.
There we go.
And you have corrective actions located on the bottom.
So for this, I can set in construction mode.
Remember, I spoke a little bit about it already.
Construction mode is a line
that's only going to be used internal to the sketch,
or a point in this case.
So, if you need that point as a reference,
you can just set it into construction mode.
If you realize, well, I don't need that bit
of geometry, you can come over here
and say delete geometry.
You'll notice that it removes it from the list
and the geometry is now gone.
Next is, I have this line.
And as I look at this, this is just a view
of the previous sketch orientation.
It's just saying, "Hey,
"this is the orientation of the sketch."
And it highlights that line, as you can see here
in the window as well.
And once again, if you need that line,
you can set it into construction.
If you realize, you know what,
I really don't need this line,
you can delete it.
So I delete it, and you'll notice
that there was a corrective action that took place.
More than one thing was fixed.
And in this case, I had one line laying
on top of another line.
They were perfectly identical.
So as the sketch sees it, it has two options
with two different lines.
So it came up with few potential issues.
So by cleaning up that one line,
it cleaned up those other potential issues.
Now you'll notice that I have implicit profile
and that profile is closed.
So as you can see here, I have a nice closed-off profile.
If I go to use edges, this is going to give me
information about if I have any external links
outside of the sketch.
Next, I have diagnostic.
Under here, this is going to let me know
if I have everything constrained correctly.
And currently, everything says ISO constrained.
So what I'm going to do is I'll just close it out
and I'll just delete one of these dimensions.
Just so you can see, click my icon,
what happens when I have something under constraint.
And you can see that it points out
those elements that are now under constraint.
If you have overconstrained elements,
it'll do the same thing.
It'll list them in here as conflicting
or overconstrained as well.
So, I'll go through.
I'll put in this angular dimension.
And I'm going to go ahead and accidentally double up
on some constraints.
So you can see here, I have some purple lines.
These are overconstrained.
This is already telling you that's 400.
This is redundant, so it doesn't need it.
So when I go into my sketch tools,
our sketch analysis, diagnostic,
you can see that line is overconstrained
and it points out everything that's overconstrained.
So, is it the line that's the problem?
Or is it dimension that's the problem?
And you'll see this offset.
There's over-constrained offset.
There's an over-constrained offset there as well.
I can come in here and just simply delete
that over-constrained offset.
So, this menu again allows you to go
and quickly analyze a sketch,
make sure you don't have any offending geometry
or offending constraints.
That way, when you're done with a sketch, you exit out.
You can use it for making your pads,
your pockets, revolves,
any of those secondary functions to make your solid.