- [Narrator] Now that I have all the necessary inputs,
the tooling inputs and the parameters, I'm going to
go ahead and create my B-side, give it
just a thickness to work off of.
So, the way I'm going to do that is generate some
flange surfaces and going to link
everything back to those parameters.
I'm going to start out with inserting another geoset.
Again, this is for organizational purposes,
this isn't necessary, but it's really nice to make
sure you have everything organized nice and clean like.
So, this is just B-side.
Now that I have my geoset in place, I'm going to
go ahead and create a boundary.
I try not to use the edges off
of a surface, a boundary representations.
So, by creating a boundary on the actual surface
I don't have to worry about if I have a new edge.
The boundary is just a new feature that the system's
going to use to always drive the flange off of.
It just creates a little bit more stability in the model.
Next, I'm going to go ahead and generate a sweep.
That sweep is going to be a linear sweep.
And the subtype is with draft direction.
The guide curve is that boundary and
the draft direction is my die line.
So, with that die line, I want to
make sure that I come 3 degrees off.
That way the part can come apart from the tool.
So, as the core moves away from the cavity
the part should be able to release from the tool.
And to get that, I'm just going to go into my angle,
highlight the field, hit the Equals on the keyboard,
hit Enter, and then pick draft.
You'll notice that, I have four options,
basically which direction do you want this to go in.
I want this to be open to draft
in this direction, so that's correct.
Give it a length.
We'll say twenty-five.
And then I want to go in the opposite direction as well.
I like to make things big, slap things out.
Generally, it's better to do that
and then trim things back.
Select Okay, and there is my return,
or my flange back up to my parting surface.
Now that I have that return, I need to
fillet everything together.
So, I'm going to go into shape fillet.
I want to fillet the initial primary slab.
That's styling input.
I want this to go in that direction.
Next is going to be my sweep.
Again that's going to point into the part.
That's the direction where the fillet's going to step.
I want a chordal fillet, so it gives it a
nice profile, a nice look all the way around.
And for the length, I'm just going to
do again Equal, Enter, pick my corner radius,
and simply select Okay.
With that, I'm going to go ahead and trim these two
together, the parting surface and my fillet.
This is going to give me an enclosed volume,
but it doesn't give me a solid.
So, I'll go into the trim function,
select my fillet, select my parting surface,
make sure you're keeping the interior region,
so I'll just hit the other side.
Select Okay, and just like that, I have
an enclosed volume of surfaces.
Still not a solid.
So, I'm going to switch my workbenches.
I'm just going to go into part design,
and inside of part design I
have a tool called "close."
You'll see this little warning pops up.
This is just telling you that it can't
make the solid inside of the B-side geoset.
Solid geometry has to go into a PartBody.
So, in this case, it's going to just automatically
change my inwork object to the PartBody.
Just Okay past that.
And you'll see that here's the CloseSurface
where it wants to appear.
Pick my trim, select okay, and go ahead and hide the trim.
I'll just hide the boundary as well.
Just like that you have an actual volume solid.
Now, my preference is to change the color,
change some properties here so I know exactly
what I'm working on and what's going on.
Just change it to purple.
You can change this to any color that you want.
Select okay, and there is my final solid.