- [Instructor] Let's learn about bringing model views
into a drawing.
Now, I've got this part right here
and I want to create a drawing for it.
So, one of the easiest ways to do that
is to come up here under file
and say make drawing from part.
That should open up your new SolidWorks'
document dialogue box,
and I can choose which template I'd like to use.
I'm going to go ahead and use the LinkedIn template drawing,
to which I've already added.
But it doesn't really matter which template you're using.
Choose anyone you have on your system,
click on OK and now we've got a drawing.
When you first open up a drawing,
more than likely you get this view palette
that shows up over here,
and it shows you all the different views
you have of your model,
and I can bring any one of those in
just by dragging and dropping that view onto my drawing.
Now, choose wisely here,
because this view you're going to be bringing into your drawing
is what is going to control all the other views.
So, I'm going to choose the top view,
which makes a lot of sense here.
And then as soon as you've placed that view,
notice what happens.
You actually have the projection view turned on.
So, anywhere I place or go around my original view here
I'm getting these projections.
And any one of these views I'd like, I can just click
and it's going to place that projection.
If I want to come up here and do an asymmetric, click there,
if I want one up top, over here.
Just place these views however, many you want.
Now, the general rule thumb here
is we don't want to place too many views.
If you get excited you start placing
a hundred different views in here,
it's not really going to help you out.
Hit Escape when you're done.
So, in this case I don't really need this view down here,
hit the delete, get rid of that guy we don't want that one.
Because there's nothing really on that face
and same thing over here there's nothing on that face.
So, we don't really need to add those views in.
So you'll want to have the minimum amount of views possible
to fully define your part.
I can move those views around,
but notice if I move this view here,
I can only move it right or left.
I can't go up and down because it's a direct projection
from this top view.
Same thing over here,
I can only go up and down with this view
I cannot go right or left.
And if I move this guy everybody follows around.
The asymmetric view doesn't really care, he can go anywhere.
That's one way to bring in views.
Now, I'm go ahead and just delete these views
from my drawing.
So we're starting back with nothing
and I'ma show you one other way to bring in views.
So over here, I have the option under drawings
to bring in a model view.
And I already have one document open
but if you had multiple documents,
they'd show up in this list right here
or you can also browse to a different part.
Once you have that, you can click on next
and now what you're going to get is multiple views.
So, I can see what the views are
but I can't see it right here.
So, if you go ahead and click on this preview button,
now I can see the view,
and I can switch to different styles of view
just by clicking on them over here
and seeing which view I want to bring in.
So, there's that top view again,
click on that one and that brings it in.
And notice over here, if I escape out of that,
here's that view, click on it.
It's using the default configuration of the part.
But if you had multiple configurations
you could choose which one of those configurations
you'd like to see in your drawing.
And you can also come down here
and take a look at the display style.
I can switch over here to a shaded with edges view
or I can do a wire frame, I can do a bunch of things here
to show that on my drawing differently.
I can click over here on high quality or draft quality,
I can adjust the sheet scale, the projection,
I can do all kinds of different things here.
When you're done click OK and you're all set.
Now, if this view happen to show up on your drawing
a little bit too big or a little bit too small,
you can always right click here,
anywhere in the area that does not have a part
and come over and make sure you're turning on properties
and right in there, I can choose the scale.
So, if I want to make it a little bigger,
I could say like two to one and then apply those changes
and notice the part is twice as big.
And if you actually click on the part here,
that same scale is shown up down here.
It's using the sheet scale.
But if you wanted to make a custom scale,
you could switch to custom scale here
and then change to a different scale.
But it's always a good idea to kind of use that sheet scale
and then just modify it by right clicking,
come over to properties,
and then modify right here with the scale.
That way everything in the drawing will be the same scale
and it all makes sense.
And most the time that scale does show up
right down here in your drawing template,
telling everybody in the world who's reading your drawing,
which scale you actually have going on in your drawing.
Anyways, that's how you bring in model views to your drawing
adjust size, the scale and the way it looks on your drawing.